Wire EDM is the process engineers reach for when a part is too hard, too precise, or too delicate to cut with a spinning tool. Punch and die sets, keyways, gear profiles, thin slots, and features cut after heat treat all end up on the wire. The process is slower than milling, so designing parts with wire EDM’s strengths and limits in mind saves real money.
How wire EDM works
Wire electrical discharge machining cuts with a thin brass or coated wire, typically 0.004″ to 0.012″ in diameter. The wire carries an electrical charge, and controlled sparks between the wire and the part erode material while deionized water flushes the debris away. The wire never touches the part, so there’s no cutting force, no tool deflection, and no burr.
That gives wire EDM three advantages over milling:
- Hardness doesn’t matter. Hardened tool steel, carbide, titanium, and nickel alloys like Inconel cut as predictably as soft steel.
- Thin and delicate features hold shape. With no cutting force, narrow ribs and thin walls don’t push away from the tool.
- Tight tolerances and fine finishes. ±0.0005″ is common, ±0.0001″ is achievable on precision machines, and skim passes produce surface finishes in the 8 to 16 µin Ra range or better.
The main limit: wire EDM only cuts electrically conductive materials. Plastics, ceramics, and glass need another process.
Design rules for wire EDM parts
Inside corners
Wire EDM produces much smaller inside corners than milling, but not perfectly sharp ones. The smallest inside radius equals the wire radius plus the spark gap. With a common 0.010″ wire, that works out to roughly 0.006″. If you need a smaller radius, the shop can switch to a finer wire, which cuts more slowly.
Outside corners can be sharp. If a sharp inside corner is functionally required, say so on the drawing so the shop plans the wire size from the start.
Start holes
Wire EDM cuts from an edge or from a hole. For an internal feature like a closed pocket or a die opening, the wire has to be threaded through a start hole first. Show start hole locations, or allow the shop to choose them, and keep them in scrap areas so they don’t affect the finished part. In hardened material, start holes are usually drilled before heat treat or made with a small-hole EDM drill.
Taper
The upper and lower wire guides can move independently, so wire EDM can cut tapered walls and different profiles on the top and bottom of a part, which is useful for die clearance. Small tapers are routine. Steep tapers often need special guides, flushing components, and softer wire, so check with the shop before designing a part around a steep angle.
Thickness
Wire EDM has no hard thickness limit in practice, but cut speed drops as thickness increases, especially in hardened tool steel and nickel alloys. Very thick sections, above roughly 4″ (100 mm), get time-intensive. If most of the material can be removed by milling, rough it first and leave wire EDM for the final profile.
Flushing and part design
Through features flush better than blind ones, and good flushing means a faster, more accurate cut. Wire EDM cuts all the way through the part, so it can’t produce blind pockets or features that stop partway down. That’s a job for sinker EDM or milling.
Tolerances and surface integrity
Wire EDM’s accuracy comes partly from multiple passes: a rough cut followed by one or more skim cuts at lower power. Each skim pass improves accuracy and finish and adds time. Specify the tolerance and finish the feature actually needs, and relax them elsewhere. Our post on what ±0.001″ actually means covers the cost side of tight tolerances.
The spark process leaves a thin re-solidified layer on the cut surface, often called the recast layer. Skim passes reduce it. For fatigue-critical aerospace parts, some specifications limit recast thickness or require its removal. If your part has one of those requirements, include it on the drawing.
When to choose wire EDM
| Choose wire EDM when | Choose milling when |
|---|---|
| The material is hardened or very tough | The material is soft or non-conductive |
| Inside corners need very small radii | Inside radii can match standard end mills |
| Features are thin, narrow, or delicate | Features are robust |
| Tolerances are ±0.0005″ or tighter | Tolerances are ±0.002″ or looser |
| The profile goes all the way through | Features are blind pockets or 3D surfaces |
Wire EDM is common in defense components, tooling, and medical instruments, where hardened materials and precise profiles meet.
How PE sources wire EDM work
PE’s CNC machining network includes wire EDM alongside milling, turning, and grinding, so parts that need roughing, heat treat, and a final wire profile can be routed through the right shops in sequence. Our engineering team reviews corner radii, start holes, and tolerance callouts before quoting, and every part is inspected in San Clemente before it ships.
Frequently asked questions
Standard wire EDM commonly holds ±0.0005″, and precision machines can reach ±0.0001″ with multiple skim passes.
Nearly. The smallest inside radius equals the wire radius plus the spark gap, roughly 0.006″ with a 0.010″ wire. Finer wire produces smaller radii at slower cutting speeds.
Any electrically conductive material, including hardened tool steel, stainless, carbide, titanium, Inconel, aluminum, copper, and brass. It can’t cut plastics or ceramics.
Send us the drawings.
A real person will contact you within 24 hours.
